The time has come to close up shop for this year.

It´s time for the last tutorial of 2010, and what better way to close up with a Spatial Sketch tutorial by SAG.

Can´t wait for next year, big things awaiting. I even got a surprise or two in store for you!  ;-)

So i wish you all a Happy New Year, see you on the other side!

(This tutorial is also available as a video on the TopSolidBlog YouTube Channel.)

How two create a handlebar using Spatial Sketch in TopSolid 7.

Tutorial by SAG

_

Create a new Part.

Create a Spatial sketch.
Only the Interactive mode should be checked.

Click the intersection of the axes.
Click a point on the Y axis and a second perpendicular to the 2nd point.

Press Ctrl Space to tilt the plane of 90 ° or use the shortcut menu: 2 times in our case.

Press the A button to switch to Arc.
Press the A button to switch to draw the line for the last segment.

Sketch dimensioning.
Contextual menu, Constraint
Click the dimension and enter the value: 150mm

Adjust the values as below.
Add a 50mm radius.

Contextual menu and choose pipe.
Select the Tube mode and set the diameter = 28mm and thickness = 1

Creating the pattern and symmetry Union by plane symmetry.
Select the plane of symmetry and position of the symbol.

Your handlebars at this stage:

Changing the angle of the handles.
Right click for Contextual menu and then choose edit the path.
Select the constraint of orientation of the plane of the arc and then delete.

Move the segment down as below.

Contextual Menu on the arc and then create a plane.

Set a constraint between this plane and the XZ plane and adjust the angle to 15 °

Exit the sketch.